{'fraction_non_alphanumeric': 0.02937926878264363, 'fraction_numerical': 0.01687424668541583, 'mean_word_length': 4.978084659261483, 'pattern_counts': {'":': 0, '<': 0, '<?xml version=': 0, '>': 0, 'https://': 0, 'lorem ipsum': 0, 'www.': 0, 'xml': 0}, 'pii_count': 0, 'substrings_counts': 0, 'word_list_counts': {'cursed_substrings.json': 0, 'profanity_word_list.json': 0, 'sexual_word_list.json': 0, 'zh_pornsignals.json': 0}}
Finite Element Analysis of Cracked One-Way Bubbled Slabs Strengthened By External Prestressed Strands

Bubbled slabs can be exposed to damage or deterioration during its life. Therefore, the solution for strengthening must be provided. For the simulation of this case, the analysis of finite elements was carried out using ABAQUS 2017 software on six simply supported specimens, during which five are voided with 88 bubbles, and the other is solid. The slab specimens with symmetric boundary conditions were of dimensions 3200/570/150 mm. The solid slab and one bubbled slab are deemed references. Each of the other slabs was exposed to; (1) service charge, then unloaded (2) external prestressing and (3) loading to collapse under two line load. The external strengthening was applied using prestressed wire with four approaches, which are L1-E, L2-E, L1-E2, and L2E2, where the lengths and eccentricities of prestressed wire are (L1=1800, L2=2400, E1=120 and E2=150 mm). The results showed that each reinforcement approach restores the initial capacity of the bubbled slab and improves it in the ultimate load capacity aspect. The minimum and maximum ultimate strength of strengthened cracked bubbled slab increased by (17.3%-64.5%) and (25.7%76.3%) than solid and bubbled slab, respectively. It is easier to improve behavior with an increased eccentricity of the prestressed wire than to increase its length.


INTRODUCTION
The method of finite elements is based on the thought that each system is physically composed of varied components, and thus its solution could even be represented in parts. Moreover, the solution is represented over each part as a linear combination of undetermined parameters and known position, and possibly time functions. The shape, material properties, and physical behavior of the parts can differ from each other. Even if the system has one geometric shape and consists of one material, representing its solution in a piece-wise manner is simpler. There are basically two nonlinearity sources: geometric and material. The geometrical nonlinearity is created purely from geometrical consideration (i.e., nonlinear strain-displacement relationship). The second material nonlinearity is attributable to nonlinear constitutive material behavior. A third type may arise due to variation in initial or boundary conditions (Reddy, 2004).
ABAQUS is also used to study simple structural problems (stress/displacement). It really can simulate problems in specific, numerous contexts as heat transfer, mass diffusion, electrical component thermal management (coupled thermal-electrical analysis), acoustics, soil mechanics (coupled pore fluid stress analysis) as well as piezoelectrical analysis (ABAQUS, 2016). The mathematical formulation of physical problems supported assumptions that certain quantities may be neglected may reduce the matter to a linear one. Linear solutions are simple and have fewer computational costs than nonlinear solutions.
There are many numerical analyzes of conventional bubbled slabs with various parameters such as slab thickness, bubble diameter and configuration, top and bottom longitudinal reinforcement, etc. The findings of a numerical study conducted by (Bindea, et al., 2015) showed even under a longitudinal reinforcement rate of less than 0.50 percent, flat slabs containing spherical voids do not struggle to shear force, and over this amount, the effective shear force declines compared to solid slabs also as the rate of reinforcement increases.
A numerical investigation (Pandey and Srivastava, 2016) evaluated the highest moment and shear force by applying the 100kN moving load on the bubble deck slab and the solid deck slab. The results indicated that, under the same conditions, the maximum moments, shear force with in-plan stress in the bubble deck were 10-25 percent below that of the solid concrete slab. A study of finite elements on the voided 100 mm thick slab and varied spacing of void formers was done. Results showed they tend to behave exactly like a solid slab as the slab's spacing increases (Subramanian and Bhuvaneshwari, 2015).
Very few theoretical studies have adopted the strengthening of bubbled slabs using FRP such as (Jasna, and Vishnu, 2018; Reshma, and Binu, 2015; 2016). An experimental and theoretical study conducted by (Oukaili and Yasseen, 2015) investigated the effect of internal strengthening using initial pre-tensioning strands on the general behavior of one-way bubbled slabs in aspects of deformation and ultimate load. The results viewed that the partially prestressed strengthening enhanced the previous aspects.
For strengthening of reinforced concrete T-beam using external post-tensioning technique with different lengths and eccentricities of prestressed strands, research by (Said, et al., 2015) showed that this technique increased the ultimate capacity of the strengthened beams and reduced the deflection and strains a same stage of loading.
As per a review of the literature that included experimental and numerical research papers to strengthen just one way bubbled slab during serviceability, it is often said that this numerical study might even be the primary one in this field. One loading stage is simulated for ordinary solid and bubbled slabs, and three for strengthening.
The major parts of a bubbled deck slab are six in this study: concrete blocks, reinforcing steel bars and anchor bolts embedded inside the concrete, upper steel plate under monotonic loading, lower steel plate as boundary conditions, and upper and lower stiffener steel plates for external reinforcement.

2.NUMERICAL WORK 2.1 General
If conducted with appropriate boundary conditions and material properties, the finite element method will provide in-depth knowledge about member's behavior. The obstacle of accomplishing FEA is time-consuming, and getting properties of materials for patterns of crack propagation can also be a complex process. Slabs that consume plenty of the concrete in any structure require only a smaller amount of concrete to carry all the hundreds applied to them. Therefore the inactive concrete, which is usually in the core zone, will have to be removed to optimize the concrete slab consumption. Since the concrete used is reduced, the slab's selfweight and therefore, the entire structure is reduced.

Material Modeling of Concrete
ABAQUS / Standard does have three models for concrete behavior; smeared cracking, brittle concrete cracking model, and damaged plasticity. Attributable to the oriented concepts of damaged elasticity, the constitutive calculations are affected by the crack. These concepts are administered after failure cracking to elucidate the material reaction's reversible neighborhood (Chaudhari and Chakrabarti, 2012). However, due to the convergence problems that may be caused by the non-existence of cyclic/unloading response or the damage within the elastic stiffness likely to result from plastic strain (Daud, 2015). It is difficult to make the model suitable for 3D applications. Also, the damaged plasticity model is used in structures undergoing dynamic or cyclic loading due to the potential for anticipating the test's behavior to failure (Rusinowski, 2005). For the above reasoning, the damage plasticity model was used during serviceability to analyze the strength of cracked bubbled deck slabs. The damage parameters can range from zero (characterizing the undamaged material) to at least one (characterizing total loss of force). The default plasticity of injury is often illustrated using

Plasticity parameters
The five parameters required for definition are: ψ is the dilation angle where it represents the proportion of the quantity modification to shear strain. ε, a parameter referenced as flow potential eccentricity, εbo /εco is that the proportion of initial equibiaxial compressive strength to initial uni-axial compressive strength. μ is the viscosity parameter that represents the viscoplastic recovery time and typically aims to enhance the convergence speed of the slab model in the softening region. It is presumed to be zero, so the slab model won't cause severe convergence complexity.
Consequently, within the present research, no viscoplastic regularization is conducted, and Kc is that the ratio of the second stress invariant to the tensile meridian (T.M.) thereto to the compressive meridian (C.M.) and it represents the yield surface in deviator plane, as shown in

Compressive behavior
Just after the elastic region, the uniaxial compressive stress-strain relationship for plain concrete must be defined. According to ABAQUS, the ranges of hardening as well as strain softening are expressed in terms of compressive stress, and elastic strain ∼ . Throughout this research, the finite element method identified the uniaxial concrete model (British Standards, 2004, Eurocode 2).

Tensile behavior
There are three main approaches available in ABAQUS/standard to understand the post cracking tension softening curve by identifying strain, crack opening (displacement) or fracture energy, as seen in Fig. 3. The relationship of tensile stress-strain softening, supported strength criterion could introduce mesh sensitivity within the causes of plain concrete (Abdullah and Bailey, 2010).

Tension stiffening model
Because the cracked concrete will initially carry some tensile stresses within the normal direction of the crack due to the concrete and steel reinforcement interaction, the tension stiffening effect is taken into account. This will be done by assuming that the concrete stress component normal to the cracked plane is gradually released. Tension stiffening models supported strength criteria represented by three curves within the current analysis: linear, bilinear, and exponential curves.

Input Data
In Figs. 5, and 6, all required parameters such as strength fcu, Youngs Modulus, and stress-strain curve data points are shown. For several other parameters needed, including the dilation angle, the eccentricity / , . The viscosity parameter, the default data of ABAQUS or on the brink of it are shown in Tables 1, 2, and 3.      Fig. 7 illustrates steel compressive uniaxial and tensile stress-strain behavior. Besides, steel reinforcement is used in the classical plasticity model for elastoplastic hardening material supported by steel. Table 4 shows the true stress input and true strain used in this analysis.

Element Types and Interaction
The bubbled deck slabs are modeled in three dimensions, which are modeled using standard 3D stress elements for all components except the reinforcements. These elements provided the acceptable rules of integration, which embraced the specimen's experimental response. Reinforcement is most often modeled using elements such as solid, beam, or truss. The use of solid elements is computationally costly, and therefore not selected. Because the reinforcing bars do not provide a really high bending rigidity, truss elements are used and modeled as an embedded element. It is assumed that their contact with the concrete is perfectly bonded. The reinforcement slip is often patterned by modifying concrete behavior. This is not studied within the current work, however. For the modeling of solid concrete slabs, an 8-node linear brick (C3D8R) element is used. The element tends to be not stiff enough in bending and stress, strains within the integration points are the most accurate. The C3D8R element integration point is located within the middle of the element. Therefore small elements are required at the boundary of a structure to capture a stress concentration. The same brick element (C3D8R) is used in the modeling of steel sheets under line pressure, steel boundary support sheets, anchor bolts, and the upper and hence the upper and lower steel sheets for strengthening. A 4 node linear brick (C3D4) tetrahedron element is used for concrete bubbled slabs to indicate an adequate representation between solid and voided concrete masses. On the other hand, a linear 3D two-node truss element with three degrees of freedom at each node (T3D2) is used for the embedded reinforcement bars. Fig. 8 Shows the element of 8-node brick and 4-node tetrahedron with integration point. Solid spheres with a radius (100 mm) are made and moved to the right positions within the solid slab block and, by subtracting all the solid spheres from the solid slab, the voids are to be formed within the cross-section center. The formulation of the finite interaction elements introduced in the modeling is based primarily on the kinematic method: interaction without penetration and conditions of friction are described kinematically at the nodes. Individuals expressed in terms of force and displacement.

Boundary Conditions
The slabs had been tested with simple supports for all the specimens. One support provided both vertical and longitudinal displacements (directions y and z) with restrictions while enabling rotations around (x-axis), (hinge support). The second support restricted only vertical displacements (direction y) whilst still allowing longitudinal displacements and rotations around the x-plane axis (roller support).

Modeling of Applied Load
The loading conditions were simulated in ABAQUS, using the load step process, as two line load on models during tests. The effective length (L), width (B), and height (H) of solid and bubbled slabs are 3000,570 and 150 mm, respectively. The total length is 3200 mm. The force was modeled as loading pressure to avoid the exposure of concrete elements to the high concentrated stresses that result in early cracking, resulting in early divergence in the analysis. The distance between the charging of two lines is 800 mm. The distance between the two prestressed wires is 300 mm. For the simulation of external prestressed force (30 kN) within each wire, the approach of applying the action of this force within the specific nodes is adopted instead of prestressed wire simulation.

Meshing of the Model
Analysis of finite elements requires model meshes. In ABAQUS, the mesh module process contains capabilities that help the meshes' auto-generation on the created parts and assemblies. Two kinds of meshes are used during this study: one for solid slabs and one for bubbled slabs. Fig. 9 illustrates the top and bottom steel meshes of all solid slabs consist of 8 bars ø10 mm as longitudinal reinforcement and 44 bar ø 10 mm as shrinkage and temperature reinforcement in the transversal direction. One simulation for the solid slab is adopted, as shown in plate 1, according to what has been mentioned previously. Plate 1. Solid slab SD with brick element mesh. Fig. 10 shows the diameter, transversal, and longitudinal arrangements of spherical voids in all bubbled slabs. The bubble (D) diameter is 100 mm, and the center to center distance between bubbles in transversal and longitudinal directions(S) is 140 mm. Same top and bottom meshes of reinforcement of SD are used in bubbled slab BD with rearrangement of bars due to insert bubbles. To achieve the aims of this study, all the bubbled slabs are simulated in the same way as shown in plates 2 and 3.

Plate 2. Isometric see-through view of bubbled slab BD.
Plate 3. BD bubbled slab with tetra mesh.

Modeling of Strengthen Cracked Bubbled Deck Slab BD
Because the; (1)simulation of the reinforcement of any cracked bubbled deck slab is the same for all bubbled specimens,(2) the purpose of numerical analysis using the ABAQUS program is to guide the potential of this program both in simulation and in case study resolution, the bubbled deck slab BD is chosen to be reinforced with four approaches L1-E1, L2-E1, L1-E2, and L2-E2. In this study, L1 and L2 are lengths of prestressed wires, and E1 and E2 are the eccentricity of them (distance from the level of prestressed wires to the center of the slab). L1=1800mm, L2= 2400mm (short and long prestressed wire, E1=120mm, and E2=150 mm (small and large eccentricity of prestressed wire). The ratios of L1/L, L2/L are 0.6, 0.8(strengthening ratios), and Figure 11. The idealization of Load-Deflection of strengthening of the cracked bubbled deck slab.

Fig.12
illustrates the load-deflection response of SD, BD, BD-L1-E1, BD-L2-E1, BD-L1-E2, and BD-L2-E2. It is evident that the bubbled slab BD shows an increase in deflection than SD and all other models at the same loading stage due to a reduction in BD stiffness resulting from inserting voids inside the slab core. On the contrary, the cracked bubbled slab's strengthening with four strengthening approaches L1-E1, L2-E1, L1-E2, and L2-E2 increased the upward deflection (camber), respectively. The ultimate load and deflection of the reinforced cracked bubbled slab with any reinforcement approach increased than conventional solid and bubbled slabs, as shown in Table 5. It is evident that increasing prestressed eccentricity is more effective in increasing the ultimate load rather than increasing the length of prestressed wire.   It is clear that the cambering increased with increasing length and eccentricities of prestressed wire. Also, the ultimate strength of solid model SD is larger than BD by 7.1% due to insert the bubbles in the core of the slab, which reduces the stiffness of the bubbled section. From Table 5, it is evident the minimum and maximum ultimate strength increased than solid and bubbled slab by (17.3%-64.5%) and (25.7%-76.3%) respectively. The ABAQUS software succeeds in simulating and modeling the problem and solution of the cracked bubbled section.
The final deflection and cambering of all models are obtained. For the briefing, some models as examples are given in plates 7-10.
Journal of Engineering Volume 27 January 2021 Number 1 64 -The conventional bubbled slab showed an increase in deflection rather than a solid slab at the same stage of loading due to the reduction of its stiffness resulting from eliminating concrete from the slab core. Also, the ultimate load of a bubbled slab decrease than a solid slab by 6.6% This finite element study's main aim is achieved by using an external post-tensioning technique to strengthen cracked bubbled deck slabs.
-The applying of external strengthening in stage two has closed the initial flexural cracks of the first stage; thereby, the bubbled section restored its ultimate strength and enhanced it.
-The conventional bubbled and solid slabs showed an increase in deflection at the same stage of loading rather than any strengthened slabs.
-The stiffness of the strengthened cracked bubbled slabs increased with increasing the strengthening ratio from 0.6 to 0.8. Also, the stiffness increased when the depth ratio increased from 0.8 to 1.
-The minimum and maximum ultimate strength of the strengthened slabs increased than solid and bubbled slabs by (17.3%-64.5%) and (25.7%-76.3%) respectively. -Increase the eccentricity of prestressed wire (depth ratio) is more effective in increasing the ultimate load than increasing the length of prestressed wire (strengthening ratio). In other words, using the strengthening ratio 0.6 with depth ratios 0.8 and 1 are better than using the strengthening ratio 0.8 with depth ratios 0.8 and 1.
-The highest ultimate strength is achieved by using strengthening ratio 0.6 and depth ratio 1.
-All the models failed in flexural failure mode after yielding bottom longitudinal reinforcement except the models strengthened by strengthening ratio of 0.8 with both depth ratios of 0.8 and 1which failed in shear mode. In other words, the failure mode changed from flexure to shear when the strengthening ratio changed from 0.6 to 0.8. This may be due to extend the length of prestressed wires more than an acceptable limit in the shear zone (strengthening ratio 0.8) and the secondorder effects.
-ABAQUS software succeeds in modeling the specific problem of cracked bubbled section and the solution of its strengthening.